I am curious to know more about the use of teardrops in PCB designs. Do you incorporate teardrops in your designs? Are there any potential drawbacks or considerations to be aware of, provided they adhere to DRC clearance rules?
Teardrops are useful, especially for narrow track widths (typically 5 mils or less), where they enhance mechanical strength and reduce stress at trace-to-pad junctions. For wider tracks, the benefits are generally less significant, and their use may not be necessary.
The process of adding and removing teardrops can vary depending on the design tool. In some cases, if teardrops are managed as a secondary step, issues can arise, such as leftover teardrop regions when traces are removed or modified. This can lead to additional cleanup work unless addressed promptly.
For designs with narrow tracks or in situations where added robustness is required, teardrops are worth considering. Ultimately, the decision depends on the specific design requirements and how well your design tool integrates teardrop functionality
1 Like
For designs with adequate annular ring sizes, teardrops may not always be necessary. Large annular rings, particularly those sized to prevent breakout, can mitigate many of the mechanical reliability issues that teardrops are intended to address.
For track widths of 10 mils or greater, and with annular rings of similar dimensions, the need for teardrops is significantly reduced, as these features already provide sufficient mechanical strength and stress relief. However, for narrower tracks, such as those below 6 mils, teardrops may still offer an added layer of reliability.
While reliability concerns related to breakout and stress at junctions are often cited, these have not posed significant issues in many designs with wider tracks and large annular rings. Ultimately, the decision to use teardrops should consider the specific track dimensions, the annular ring size, and the overall mechanical requirements of the PCB.
1 Like
Teardrops can be optional for rigid PCBs, as modern CNC drilling ensures reliable via or thru-hole pads if you adhere to the manufacturer’s guidelines for drill size and annular rings. However, adding teardrops is often beneficial and incurs no extra cost if there is sufficient clearance.
For flexible PCBs, teardrops are essential. They minimize stress concentration at pad and via junctions, which is critical in preventing cracks from forming due to repeated flexing. Using rounded traces instead of sharp corners further enhances durability in flex circuits.
To optimize your design, ensure that the manufacturer’s capabilities are accounted for in your EDA software and conduct a DFM test before production. Teardrops are not strictly necessary for rigid PCBs but are indispensable for flexible designs.
1 Like
For most high-quality FPGA boards, especially those with multiple layers and fine-pitch components, teardrops are typically unnecessary. Modern manufacturing processes ensure precise drilling and etching, so yield problems due to off-center THT drills are rare. If your process tolerances are poor enough to consider teardrops for THT pads, you may face broader manufacturing challenges, particularly with more complex boards like 8-layer designs.
Teardrops are generally irrelevant for THT pads in high-speed or high-current paths, as these design scenarios rarely rely on small annular rings for thermal or current handling. Instead, robust manufacturing and layout practices negate the need for teardrops in these contexts. However, for specific cases like flex PCBs or very narrow trace widths, teardrops may still provide value.
1 Like
The necessity of teardrops often depends on the capabilities of the PCB manufacturer and the design’s specific geometries. Manufacturers may add teardrops to improve yield if the combination of your design constraints and their processes benefits from them.
That said, with modern fabrication techniques, teardrops are usually not mandatory for common geometries. Always consult with your manufacturer to align your design decisions with their capabilities.
1 Like
Teardrops serve two primary functions in PCB design:
- They help avoid the formation of pockets at the junction where traces meet pads, which can trap etching acids and lead to potential issues.
- They reduce mechanical/thermal stress concentrations, minimizing the risk of hairline cracks forming in traces.
However, in modern professional manufacturing, teardrops are often unnecessary. Their inclusion might be more about aesthetics than addressing significant problems. In my experience with various boards—both with and without teardrops—I have not observed any notable differences in performance.
1 Like
Teardrops in aid in the drilling process by preventing drill breakouts at the junction between traces and vias/pads. This is crucial for narrow traces where the risk of damage during drilling is higher.
1 Like
Drilled holes can sometimes be significantly off-center from pad centers. In extreme cases, this can result in holes with little to no annular ring, making it difficult to connect to outgoing traces. Teardrops help ensure there’s enough pad material for a solid connection. However, if the misalignment isn’t in the direction of the teardrops, using larger pads is the better solution.
1 Like
We’ve found teardrops to be very beneficial in our test jig designs. The bed-of-nails jig uses spring-loaded test pins that press against the PCB, and we observed that thin traces near the test pin pads and connected traces were prone to cracking under this stress. By increasing the trace width and adding teardrop reinforcements at these junctions, the connections have become significantly more resilient.
1 Like